Home / Courses / Manufacturing / Machining Processes and Tool Life

Manufacturing · Chapter 6 of 10 · Intermediate

Machining Processes and Tool Life

Turning, milling, drilling, grinding: the workhorses of the machine shop. Each removes metal at a rate you can compute, and each wears the tool faster the harder you push, a trade-off Taylor's equation makes exact.

Readiness check

This chapter applies cutting theory to real machines. Tick only what you can do closed-notes.

Relate surface speed to rotation: V = πDN.
Compute a volume removal rate.
Work with powers and roots (for Taylor).
Recall cutting power from Chapter 5.
Read a log-log plot.

0 or 1 weak itemsContinue with this chapter.

2 weak itemsReview cutting power in Chapter 5.

3 or more weak itemsRevisit speed, feed, and depth before continuing.

The core idea

Each machining process removes metal at a rate set by speed, feed, and depth, and the cutting speed trades directly against tool life through the Taylor equation.

N = V/(πD)MRR = V·f·dVTⁿ = C

Turning, milling, and drilling differ mainly in what rotates, but all share the same trio: cutting speed (how fast the edge moves), feed (advance per revolution or tooth), and depth of cut. Their product is the material removal rate, which sets time and power. Push the speed up and you remove metal faster but wear the tool sooner; the Taylor equation VTⁿ = C captures that exchange, and it is what fixes the economic cutting speed.

The skill works when: you compute removal rate and time from speed, feed, and depth, and use Taylor to balance speed against tool life.

The skill breaks down when: speed is maximised for rate alone, ignoring how sharply it shortens tool life.

The concept. Turning: the workpiece spins at cutting speed V while the tool feeds along at f, removing a layer of depth d. Speed, feed, and depth set both the removal rate and the tool life.

The skills, taught in order

Machining is a few processes plus the economics of tool wear. Five skills cover turning, milling and drilling, grinding, tool life, and machinability.

6.1 Turning

The workpiece rotates; the tool feeds along it. The spindle speed is N = V/(πD) from the surface speed and diameter, the removal rate is MRR = V·f·d, and the time to machine a length L is t = L/(fN). These four relations plan any turning pass.

6.2 Milling and drilling

In milling the multi-tooth cutter rotates while the table feeds the work; the table feed is f_t times the number of teeth times the spindle speed. In drilling the bit rotates and feeds along its axis. Both still reduce to speed, feed, and depth setting the removal rate.

Process	What rotates	Best for
Turning	workpiece	cylindrical parts
Milling	multi-tooth cutter	flat and prismatic shapes, slots
Drilling	drill bit	holes
Grinding	abrasive wheel	fine finish, hard materials

6.3 Grinding

Grinding cuts with countless tiny abrasive grains. It removes little material per pass but gives a fine finish and tight tolerance, and it can machine hardened steel. Because the grains have very negative rake, its specific energy is high, so it generates a lot of heat.

6.4 Tool wear and the Taylor equation

Tools wear by flank and crater wear until the edge fails. Cutting speed has the strongest effect, captured by VTⁿ = C: tool life T falls steeply as speed V rises. The exponent n depends on the tool material; a larger n means life is less sensitive to speed.

Tool material	Taylor n (typical)
High-speed steel	0.1 to 0.15
Carbide	0.2 to 0.3
Ceramic	0.4 to 0.6

6.5 Machinability and optimization

Machinability rates how easily a material cuts (tool life, force, finish). Because higher speed cuts time but shortens tool life and raises tool cost, there is an economic cutting speed that minimises total cost per part, the optimization that closes the loop with Chapter 10.

Engineering connection: these relations set cycle times, spindle power, and tooling cost, the inputs to the manufacturing economics of Chapter 10.

Worked example 1: a turning pass

A 50 mm diameter bar is turned at a cutting speed of 150 m/min with a feed of 0.3 mm/rev and a depth of cut of 2 mm, over a length of 200 mm. Find the spindle speed, the material removal rate, and the machining time.

Figure 1. A turning pass. The cutting speed and diameter fix the spindle speed; speed, feed, and depth fix the removal rate; the length and feed fix the time.

ProblemFind N, MRR, and the machining time for the bar in Figure 1.
Given / findD = 50 mm, V = 150 m/min, f = 0.3 mm/rev, d = 2 mm, L = 200 mm. Find N, MRR, t.
AssumptionsOne pass, constant speed and feed, single-point tool.
ModelSpindle speed from surface speed and diameter, removal rate from speed times feed times depth, time from length over feed rate.
EquationsN = V/(πD) MRR = V·f·d t = L/(fN)
SolveN = 150 000/(π × 50) = 955 rev/min. MRR = 150 000 × 0.3 × 2 = 90 000 mm³/min = 1500 mm³/s. t = 200/(0.3 × 955) = 0.70 min (about 42 s).
CheckAt 90 000 mm³/min and a steel specific energy of ~2.8 J/mm³, the power is about 4.2 kW, in the range of the Chapter 5 example, a useful consistency check.
ConclusionSpeed, feed, and depth fully plan the pass. Doubling the feed would halve the time and double the power, the first lever a process planner reaches for, within the tool's limits.

Result. N = 955 rev/min, MRR = 90 000 mm³/min, machining time ≈ 0.70 min.

Worked example 2: tool life with Taylor's equation

A carbide tool obeys Taylor's equation VTⁿ = C with n = 0.25 and C = 400 (V in m/min, T in min). Find the tool life at 250 m/min, and the cutting speed that gives a one-hour tool life.

Figure 2. On log-log axes the Taylor equation is a straight line: higher speed gives shorter life. Dropping from 250 to 144 m/min stretches tool life from 6.5 minutes to a full hour.

ProblemFind the tool life at 250 m/min and the speed for a 60 min life, for the tool in Figure 2.
Given / findn = 0.25, C = 400. Find T at V = 250, and V for T = 60.
AssumptionsConstant feed and depth, Taylor's equation holds over this range.
ModelRearrange VTⁿ = C for T given V, and for V given T.
EquationsT = (C/V)^1/n V = C/Tⁿ
SolveAt 250 m/min, T = (400/250)⁴ = 1.6⁴ = 6.5 min. For a 60 min life, V = 400/60^0.25 = 400/2.78 = 144 m/min.
CheckCutting speed and tool life move in opposite directions, as the equation demands. A 1.7-fold speed cut (250 to 144) buys nearly a tenfold longer life, the steep payoff that makes moderate speeds economical.
ConclusionTaylor's equation turns the speed-life trade into numbers. The best speed is not the fastest, but the one that minimises cost once tool changes and tooling price are counted, the optimization of Chapter 10.

Result. Tool life 6.5 min at 250 m/min; 144 m/min gives a one-hour life.

Misconceptions and diagnostics

Mistake	Symptom	Diagnostic question	Correction
Fastest speed is best	Tools wear out in minutes	"What does Taylor say about life?"	Higher speed slashes tool life; choose the economic speed.
Confusing speed and spindle rpm	Wrong N or surface speed	"Is this V (m/min) or N (rev/min)?"	Convert with N = V/(πD); they are not the same.
Ignoring feed in time	Machining time mis-estimated	"Did I use t = L/(fN)?"	Time depends on feed rate fN, not speed alone.
Grinding for bulk removal	Slow, hot, expensive roughing	"Do I need finish or removal?"	Grinding is for finish and hard materials; mill or turn to remove bulk.

Practice ladder

Level 1 · Direct skill

A 30 mm bar is turned at 120 m/min. Find the spindle speed.

Show answer

N = V/(πD) = 120 000/(π × 30) = 1273 rev/min. Smaller diameters need higher rpm for the same surface speed.

Level 2 · Mixed concept

Using the Worked Example 2 tool, what tool life results at 200 m/min, and how does it compare with 250 m/min?

Show answer

T = (400/200)⁴ = 2⁴ = 16 min, versus 6.5 min at 250. Dropping speed by 20% more than doubles tool life, the steep Taylor trade.

Level 3 · Independent problem

Two tools have the same C = 400 but n = 0.15 (HSS) and n = 0.5 (ceramic). Compare their tool life at 300 m/min.

Show answer

HSS: T = (400/300)^1/0.15 = 1.333^6.67 ≈ 6.4 min. Ceramic: T = (400/300)² = 1.78 min. At high speed the higher-n ceramic actually holds up worse here only because of equal C; in practice ceramics carry a much higher C, letting them run far faster. The exponent governs sensitivity, the constant governs the level.

Level 4 · Transfer to real engineering

Find a real machined part and a quoted cutting speed for its material. Estimate the spindle speed and machining time for one feature, and comment on the tool life implied.

What good work looks like

Surface speed converted to rpm, a removal rate and time computed, and a Taylor-based comment on whether the speed favours productivity or tool life.

Working with AI, and proving it yourself

Use AI as an examiner, not a solver

"Check that I converted surface speed to spindle rpm correctly."

"Give me five cuts; I will say whether the speed favours rate or tool life."

"Compute the machining time." Using t = L/(fN) yourself is the skill.

"What speed should I use?" Reasoning from Taylor and cost is the point.

Portfolio task

Plan a machining operation: compute spindle speed, removal rate, and time, then use Taylor's equation to estimate tool life at two speeds and discuss the trade.

Must include: N, MRR, and time for a pass, plus a Taylor tool-life comparison at two speeds.

Retrieval and spaced review

Closed notes. Answer out loud, then reveal.

1. Relate spindle speed to cutting speed.

N = V/(πD): surface speed over the circumference.

2. Write the removal rate and machining time for turning.

MRR = V·f·d; t = L/(fN).

3. State Taylor's tool-life equation.

VTⁿ = C: tool life falls as speed rises.

4. What does the exponent n represent?

How sensitive tool life is to speed; larger n (ceramic) means less sensitive.

5. Why is the fastest speed rarely best?

It shortens tool life sharply, raising tool and changeover cost; an economic speed minimises total cost.

TodayFinish this quiz and Levels 1 and 2 of the ladder.

+1 dayRe-derive the turning time and Taylor life from a blank page.

+3 daysOne turning and one tool-life problem.

+7 daysMove to joining and welding, Chapter 7.

+30 daysUse tool life in the cost model of Chapter 10.

Textbook mapping

Item	Mapping
Primary source	Kalpakjian and Schmid, Manufacturing Engineering and Technology, Chapters 23 to 26 (machining processes, grinding, machining economics)
Cross-reference	Groover, Ch. 22 and 23 · DeGarmo, machining chapters
Core topics	6.1 Turning · 6.2 Milling and drilling · 6.3 Grinding · 6.4 Tool life (Taylor) · 6.5 Machinability
Engineering connection	Cycle times, spindle power, and tooling cost for real production.
Read next	Chapter 7: Joining and Welding.